# Distributed heat fluxes Distributed heat fluxes are available for all elements with temperature degrees of freedom. They are specified as described in “Thermal loads,” Section 34.4.4.

Load ID (*DFLUX)	Abaqus/CAE Load/Interaction	Units	Description
BF	Body heat flux	$JL^{-3}T^{-1}$	Heat body flux per unit volume.
$BFNU^{(S)}$	Body heat flux	$JL^{-3}T^{-1}$	Nonuniform heat body flux per unit volume with magnitude supplied via user subroutine DFLUX.
Sn	Surface heat flux	$JL^{-2}T^{-1}$	Heat surface flux per unit area into face n.
$SnNU^{(S)}$	Not supported	$JL^{-2}T^{-1}$	Nonuniform heat surface flux per unit area into face n with magnitude supplied via user subroutine DFLUX.

# Film conditions Film conditions are available for all elements with temperature degrees of freedom. They are specified as described in “Thermal loads,” Section 34.4.4.

Load ID (*FILM)	Abaqus/CAE Load/Interaction	Units	Description
Fn	Surface film condition	$JL^{-2}T^{-1}\theta^{-1}$	Film coefficient and sink temperature (units of $\theta$ ) provided on face n.
FnNU(S)	Not supported	$JL^{-2}T^{-1}\theta^{-1}$	Nonuniform film coefficient and sink temperature (units of $\theta$ ) provided on face n with magnitude supplied via user subroutine FILM.

# Radiation types Radiation conditions are available for all elements with temperature degrees of freedom. They are specified as described in “Thermal loads,” Section 34.4.4.

Load ID(*RADIATE)	Abaqus/CAELoad/Interaction	Units	Description
Rn	Surface radiation	Dimensionless	Emissivity and sink temperature(units of θ) provided on face n.

Distributed loads Surface-based distributed loads are specified as described in “Distributed loads,” Section 34.4.3.

Load ID(*DSLOAD)	Abaqus/CAELoad/Interaction	Units	Description
HP(S)	Pressure	$FL^{-2}$	Hydrostatic pressure applied to the element surface, linear in global Z. The pressure is positive in the direction opposite to the surface normal.
P	Pressure	$FL^{-2}$	Pressure applied to the element surface. The pressure is positive in the direction opposite to the surface normal.
PNU	Pressure	$FL^{-2}$	Nonuniform pressure applied to the element surface with magnitude supplied via user subroutine DLOAD in Abaqus/Standard and VDLOAD in Abaqus/Explicit. The pressure is positive in the direction opposite to the surface normal.
SP(E)	Pressure	$FL^{-4}T^{2}$	Stagnation pressure applied to the element reference surface.
TRSHR	Surface traction	$FL^{-2}$	Shear traction on the element reference surface.
TRSHRNU(S)	Surface traction	$FL^{-2}$	Nonuniform shear traction on the element reference surface with magnitude and direction supplied via user subroutine UTRACLOAD.
TRVEC	Surface traction	$FL^{-2}$	General traction on the element reference surface.
TRVECNU(S)	Surface traction	$FL^{-2}$	Nonuniform general traction on the element reference surface with magnitude and direction supplied via user subroutine UTRACLOAD.

Load ID(*DSLOAD)	Abaqus/CAELoad/Interaction	Units	Description
VP(E)	Pressure	FL3T	Viscous surface pressure. The viscous pressure is proportional to the velocity normal to the element face and opposing the motion.

# Distributed heat fluxes Surface-based heat fluxes are available for all elements with temperature degrees of freedom. They are specified as described in “Thermal loads,” Section 34.4.4.

Load ID(*DSFLUX)	Abaqus/CAELoad/Interaction	Units	Description
S	Surface heat flux	$JL^{-2}T^{-1}$	Heat surface flux per unit area into the element surface.
$SNU^{(S)}$	Surface heat flux	$JL^{-2}T^{-1}$	Nonuniform heat surface flux per unit area into the element surface with magnitude supplied via user subroutine DFLUX.

# Film conditions Surface-based film conditions are available for all elements with temperature degrees of freedom. They are specified as described in “Thermal loads,” Section 34.4.4.

Load ID(*SFILM)	Abaqus/CAELoad/Interaction	Units	Description
F	Surface film condition	$JL^{-2}T^{-1}\theta^{-1}$	Film coefficient and sink temperature (units of $\theta$ ) provided on the element surface.
$FNU^{(S)}$	Surface film condition	$JL^{-2}T^{-1}\theta^{-1}$	Nonuniform film coefficient and sink temperature (units of $\theta$ ) provided on the element surface with magnitude supplied via user subroutine $FILM$ .

# Radiation types Surface-based radiation conditions are available for all elements with temperature degrees of freedom. They are specified as described in “Thermal loads,” Section 34.4.4.

Load ID(*SRADIATE)	Abaqus/CAELoad/Interaction	Units	Description
R	Surface radiation	Dimensionless	Emissivity and sink temperature (units of θ) provided on the element surface.

# Element output If a local coordinate system is not assigned to the element, the stress/strain components, as well as the section forces/strains, are in the default directions on the surface defined by the convention given in “Conventions,” Section 1.2.2. If a local coordinate system is assigned to the element through the section definition (“Orientations,” Section 2.2.5), the stress/strain components and the section forces/strains are in the surface directions defined by the local coordinate system. The local directions defined in the reference configuration are rotated into the current configuration by the average material rotation. In the case of composite shells the components of section forces, section strains, and transverse shear stress estimates for stacked continuum shells (CTSHR13 and CTSHR23) are reported in the local orientation defined for the entire section (or the default shell coordinate directions if no section orientation is used). Components of stress, strain, and transverse shear stress (TSHR13 and TSHR23) are given with respect to the individual layer orientations. # Stress, strain, and other tensor components Stress and other tensors (including strain tensors) are available. All tensors have the same components. For example, the stress components are as follows:

S11	Local 11 direct stress.
S22	Local 22 direct stress.
S12	Local 12 shear stress.

The stress in the thickness direction, $\sigma _ { 3 3 }$ , is reported as zero to the output database as discussed in “Abaqus/Standard output variable identifiers,” Section 4.2.1. $\sigma _ { 3 3 }$ may be obtained through the average section stress variable SSAVG6. Output of in-plane stress components of continuum shell elements does not include Poisson effects due to changes in the thickness direction. # Heat flux components Available for elements with temperature degrees of freedom.

HFL1	Heat flux in the X-direction.
HFL2	Heat flux in the Y-direction.
HFL3	Heat flux in the Z-direction.

Section forces, moments, and transverse shear forces

SF1	Direct membrane force per unit width in local 1-direction.
SF2	Direct membrane force per unit width in local 2-direction.
SF3	Shear membrane force per unit width in local 1–2 plane.
SF4	Transverse shear force per unit width in local 1-direction.
SF5	Transverse shear force per unit width in local 2-direction.
SF6	Thickness stress integrated over the element thickness.
SM1	Bending moment force per unit width about local 2-axis.
SM2	Bending moment force per unit width about local 1-axis.
SM3	Twisting moment force per unit width in local 1–2 plane.

The section force and moment resultants per unit length in the normal basis directions in a given shell section of thickness h can be defined on this basis as $$ (S F 1, S F 2, S F 3, S F 4, S F 5, S F 6) = \int_ {- h / 2} ^ {h / 2} \left(\sigma_ {1 1}, \sigma_ {2 2}, \sigma_ {1 2}, \sigma_ {1 3}, \sigma_ {2 3}, \sigma_ {3 3}\right) d z, $$ $$ (S M 1, S M 2, S M 3) = \int_ {- h / 2} ^ {h / 2} (\sigma_ {1 1}, \sigma_ {2 2}, \sigma_ {1 2}) z d z. $$ where stress in the thickness direction $\sigma _ { 3 3 }$ is constant through the thickness. Outputs of in-plane section forces of continuum shell elements do not include Poisson effects due to changes in the thickness direction. Average section stresses

SSAVG1	Average membrane stress in local 1-direction.
SSAVG2	Average membrane stress in local 2-direction.
SSAVG3	Average membrane stress in local 1–2 plane.
SSAVG4	Average transverse shear stress in local 1-direction.
SSAVG5	Average transverse shear stress in local 2-direction.
SSAVG6	Average thickness stress in the local 3-direction.

The average section stresses are defined as $$ S S A V G n = S F n / h $$ where $n = 1 , \ldots , 6$ and h is the current section thickness. $\sigma _ { 3 3 }$ is constant through the thickness. Section strains, curvatures, and transverse shear strains

SE1	Direct membrane strain in local 1-direction.
SE2	Direct membrane strain in local 2-direction.
SE3	Shear membrane strain in local 1–2 plane.
SE4	Transverse shear strain in the local 1-direction.
SE5	Transverse shear strain in the local 2-direction.
SE6	Total strain in the thickness direction.
SK1	Curvature change about local 1-axis.
SK2	Curvature change about local 2-axis.
SK3	Surface twist in local 1–2 plane.

The local directions are defined in “Shell elements: overview,” Section 29.6.1. Shell thickness

STH	Section thickness, which is the current section thickness if geometric nonlinearity is considered; otherwise, it is the initial section thickness.

Transverse shear stress estimates

TSHR13	13-component of transverse shear stress.
TSHR23	23-component of transverse shear stress.

Estimates of the transverse shear stresses are available at section integration points as output variables TSHR13 or TSHR23 for both Simpson’s rule and Gauss quadrature. For Simpson’s rule output of variables TSHR13 or TSHR23 should be requested at nondefault section points, since the default output is at section point 1 of the shell section where the transverse shear stresses vanish. For numerically integrated sections, estimates of the interlaminar shear stresses in composite sections—i.e., the transverse shear stresses at the interface between two composite layers—can be obtained only by using Simpson’s rule. With Gauss quadrature no section integration point exists at the interface between composite layers. Unlike the S11, S22, and S12 in-surface stress components, TSHR13 and TSHR23 are not calculated from the constitutive behavior at points through the shell section. They are estimated by matching the elastic strain energy associated with shear deformation of the shell section with that based on piecewise quadratic variation of the transverse shear stress across the section, under conditions of bending about one axis (see “Transverse shear stiffness in composite shells and offsets from the midsurface,” Section 3.6.8 of the Abaqus Theory Guide). Therefore, interlaminar shear stress calculation is supported only when the elastic material model is used for each layer of the shell section. If you specify the transverse shear stiffness values, interlaminar shear stress output is not available. TSHR13 and TSHR23 are valid only for sections that have one element through the thickness direction. For sections with two or more continuum shell elements stacked in the thickness direction, output variables SSAVG4 and SSAVG5 or CTSHR13 and CTSHR23 should be used instead. An example using SSAVG4 and SSAVG5 to estimate the transverse shear stress distribution in stacked continuum shells can be found in “Composite shells in cylindrical bending,” Section 1.1.3 of the Abaqus Benchmarks Guide. # Transverse shear stress estimates for stacked continuum shells CTSHR13 13-component of transverse shear stress for stacked continuum shells. CTSHR23 23-component of transverse shear stress for stacked continuum shells. Estimates of the transverse shear stresses that take into account the continuity of interlaminar transverse shear stress for stacked continuum shells are available at section integration points as output variables CTSHR13 or CTSHR23 for both Simpson’s rule and Gauss quadrature. CTSHR13 or CTSHR23 are available only in Abaqus/Standard. CTSHR13 and CTSHR23 are not calculated from the constitutive behavior at points through the shell section. They are estimated by assuming a quadratic variation of shear stress across the element section and by enforcing the continuity of interface transverse shear between adjoining continuum elements in a stack. It is also assumed that the transverse shear is zero at the free boundaries of a stack. The intended use case for CTSHR13 and CTSHR23 is to estimate the through-the-thickness transverse shear stress for flat or nearly flat composite plates that are modeled with stacked continuum shell elements where each continuum element in the stack models a single material layer. Central to CTSHR13 and CTSHR23 is the concept of a “stack” of continuum shell elements. During input file preprocessing Abaqus partitions all the continuum shells in a model into stacks. A “stack” is defined as a contiguous set of continuum shells whose first and last elements lie on a free boundary and who are connected through shared nodes on the top and bottom element surfaces (as determined by the elements’ stack directions). In this context a “free boundary” is a top or bottom surface of a continuum shell element that is not connected through its nodes to another continuum shell element. For example, assuming that the stack direction of all the elements in Figure 29.6.8–1 is in the z-direction, elements 1–6 would form a stack. 

text_image

A stack of continuum shell elements 1 2 3 4 5 6 x z

Figure 29.6.8–1 Composite plate meshed with six stacked continuum shells through the thickness. It is important to emphasize that stacks of continuum shells are connected through shared nodes, not through constraints or other elements. Suppose, for example, that in Figure 29.6.8–1 element pairs 1–2, 2–3, 4–5, and 5–6 are connected to each other through shared nodes, but elements 3 and 4 are connected through a constraint (such as a tied constraint). In that case Abaqus would interpret the bottom surface of element 3 and the top surface of element 4 as free boundaries; therefore, elements 1–3 would form one stack, and elements 4–6 would form a second independent stack. For another example, suppose that element 4 is not a continuum shell element. In this case elements 1–3 would form one stack, and elements 5–6 would form another stack. In a final example, suppose the stack directions of elements 1–5 are in the global z-direction and the stack direction of element 6 is in the global x-direction. In this case elements 1–5 would form a stack separate from element 6. In the three cases just discussed the computed values of CTSHR13 and CTSHR23 would probably not be what you wanted. It is more likely that you want elements 1–6 to be in the same stack. It may be necessary to make changes in your model to achieve this. You can review the partitioning of the continuum shell elements into stacks in the data file by making a model definition data request. The continuum shell elements in a stack must satisfy certain criteria; otherwise, Abaqus marks the stack as invalid with respect to computing CTSHR13 or CTSHR23. If a stack is marked as invalid, CTSHR13 or CTSHR23, if requested, are not computed and are set to zero for all continuum shell elements in that stack. If a continuum shell element does not have an elastic material model, if you specify the transverse shear for any element in the stack, or if the element is specified as rigid, that stack is marked as invalid. A stack is also marked as invalid if the normal of any element in a stack is not within 10° of the average normal for the stack. In addition, if a continuum shell element is removed during the analysis, the stack to which the element belongs is marked as invalid until the element is reactivated. There are several other certain restrictions on CTSHR13 and CTSHR23. CTSHR13 and CTSHR23 are not available in any continuum shell element with a multi-layer composite material definition. However, having a multi-layer composite element in the stack does not invalidate the stack. For the purposes of computing CTSHR13 and CTSHR23, a maximum of 500 continuum shell elements can be put in any individual stack. If more than 500 continuum shell elements are stacked on top of each other, Abaqus issues a warning message during input file preprocessing, and CTSHR13 and CTSHR23 are not computed and are set to zero for all continuum shell elements in the model. CTSHR13 and CTSHR23 are not available if element operations are run in parallel (see “Parallel execution in Abaqus/Standard,” Section 3.5.2). CTSHR13 or CTSHR23 are currently available only for static and direct-integration dynamic analyses. An example using CTSHR13 and CTSHR23 to estimate the transverse shear stress distribution in stacked continuum shells can be found in “Composite shells in cylindrical bending,” Section 1.1.3 of the Abaqus Benchmarks Guide. # Node ordering on elements 

text_image

face 5 6 face 2 3 face 4 4 face 1 face 3 5 2

6-node continuum shell 

text_image

face 1 face 2 8 face 6 face 5 5 4 6 3 face 4 1 2 face 3

8-node continuum shell # Numbering of integration points for output # Stress/displacement analysis 

text_image

6 3 1 4 5 1 2

6-node continuum shell 

text_image

8 7 1 4 x 6 5 3 1 2

8-nodecontinuum shell